Adding Bolt Connections to the assembly

1. Click the Design Library tab on the left side of the graphics window.
2. On the Design Library tab, select Toolbox and click Add in now.
3. On the Design Library tab, click Toolbox > ANSI Metric.
4. Under the ANSI Metric folder, click Bolts and Screws > Hex Head.
5. Click Heavy Hex Bolt-ANSI B18.2.3.6M and drag it into the graphics window.

1. On the Configure Component PropertyManager, set the bolt properties as shown.

1. Click the Add button in the Part Number section and click OK.
2. Click OK on the PropertyManager. Another instance of the bolt is attached to the pointer.

1. Click Cancel to stop inserting more bolts.
2. On the Design Library tab, click Washer > Plain Washers.
3. The Regular Flat Washer and drag it into the graphics window.
4. Set the washer size to M12 and click the Add button under the Part Numbers section of the PropertyManager.
5. Click OK on the Part Number dialog.
6. Click OK and Cancel.

1. On the Design Library tab, under ANSI Metric, click Nuts > Hex Nuts.
2. Click and drag Hex Heavy Nut into the graphics window.
3. On the Configure Component PropertyManager, set the nut properties as shown.

1. Click the Add button under the Part Numbers section of the PropertyManager.
2. Click OK on the Part Number dialog.
3. Click OK and Cancel.

1. On the CommandManager, click Assembly > Insert Components > New Assembly . A new sub-assembly is inserted into the assembly.
2. In the FeatureManager Design Tree, click and drag the bolt, nut and washer into the sub-assembly.

1. Right click on the sub-assembly and select Open Subassembly. The Sub-assembly is opened in another window.

1. On the CommandManager, click Assembly > Mate.
2. Click the Multiple mate mode icon on the PropertyManager.
3. Click on the cylindrical face of the bolt, and then click the cylindrical faces of the washer and nut. The bolt face is selected as a common mate entity.

1. Click Add/Finish Mate.
2. Click in the Entities to mate.
3. Select the flat face of the bolt.
4. Select the flat face of washer.

1. Click Flip Mate Alignment , and then click OK on the SOLIDWORKS dialog.
2. Click Add/Finish Mate .

1. Likewise, align the end faces of the bolt and nut, and click OK on the PropertyManager.

1. Save and close the sub-assembly.
2. On the CommandManager, click Assembly > Mate.
3. Click on the flat face for the washer and the part with holes.

1. Click the Coincident icon, and click Add/Finish Mate.
2. Click the Cylindrical face of the bolt and circular edge of the hole as shown.

1. Click the Concentric icon, check the Lock Rotation option, and click Add/Finish Mate.
2. Click OK on the PropertyManager.